Creepage and Clearance Rules for Relay PCB Design

Aug 24, 2026 Leave a message

120A Power Relay Design Guide: Advanced Engineering for Critical Systems

Creepage and clearance rules for a relay PCB do not come from one universal "250 VAC" spacing value. Clearance is the shortest path through air between conductive parts; creepage is the shortest path along an insulating surface. The required value for each barrier must be determined from the applicable end-product standard using the insulation function, working and transient voltages, overvoltage category, pollution degree, material group or CTI, altitude, waveform, and any qualified coating or potting system.

The design rule

Calculate the product-level insulation requirement first. Then select an exact relay whose internal insulation can support that requirement, and design the PCB, solder joints, slots, connectors, hardware, coating, and enclosure so the assembled product does not create a shorter path.

A relay advertised with 8 mm coil-to-contact creepage and clearance does not automatically give the finished board an 8 mm barrier. A copper pour, via, solder fillet, test pad, mounting screw, connector shield, inner plane, contamination, or adjacent component can become the controlling path. Likewise, a board can pass a short hi-pot test while still lacking the surface distance needed for years of humid or polluted operation.

This guide is written for PCB designers, relay application engineers, OEM equipment teams, compliance personnel, contract manufacturers, quality engineers, and technical buyers. It explains the workflow and evidence to prepare; it does not reproduce proprietary standard tables or provide a certification decision.

PCB relay board showing relay packages copper areas pads connectors and other conductive features

The relay package is only one part of the insulation system. Pads, traces, connectors, hardware, solder, component leads, and both sides of the board must also be reviewed. Image: SparkFun Electronics, Wikimedia Commons, CC BY 2.0.

 

Start by Separating Six Insulation Terms

Engineers often use "isolation," "spacing," and "hi-pot" as if they describe the same property. They do not. Keep the physical path, failure mechanism, and test result separate in the design record.

Term What it describes What determines it
Clearance Shortest distance through air between conductive parts Required impulse/peak withstand, voltage conditions, field geometry, pollution provisions, altitude
Creepage Shortest path along an insulating surface Working voltage, pollution degree, material group/CTI, insulation function, valid geometry
Distance through insulation Path through solid insulating material Material, thickness, construction, aging, partial-discharge and electric-strength requirements
Open contact gap Separation between open relay contacts Internal relay construction, contact form, load and product-standard requirements
Dielectric strength A test result across a named barrier for a stated voltage, waveform, duration, and condition Test method and sample conditioning-not distance alone
Insulation resistance Leakage-related resistance under a stated DC test Test voltage, humidity, temperature, contamination, timing

A slot can lengthen the surface path while leaving the direct air path nearly unchanged. A coating can improve the local pollution environment without removing every air gap. A high dielectric-test voltage does not prove long-term tracking resistance. Store clearance, creepage, solid insulation, and test evidence as separate fields even when one physical construction supports several of them.

 

Map Every Barrier Around the Relay

Do not draw one rectangle around the relay and call it the isolation barrier. Create an insulation diagram that names every conductor pair whose failure could create shock, fire, equipment damage, or loss of a required control function. Show the relay in each contact state because the voltage map can change when COM transfers between NO and NC.

Barrier to check Typical conductors Frequently missed path
Coil to contacts MCU/driver/coil pins versus load terminals Pour, via, test pad, snubber trace, or inner copper beneath the relay
Hazardous voltage to SELV or accessible circuit Mains nets versus sensor, USB, UI, communication or low-voltage connector Connector shield, programming header, mounting hardware, adjacent board
Line to neutral or phase to phase Different mains conductors and switched nets Solder fillets, fuse/MOV leads, thermal spokes and trace necks
Contact set to contact set Poles switching different supplies, phases or domains Assuming pole separation from the schematic symbol rather than relay data
Live part to grounded or accessible metal Relay terminal or PCB pad versus chassis, shield, heat sink or screw Washer, standoff, board guide, bent lead or service movement
Board edge to external conductor Outer copper or pin versus enclosure, lug, harness or another PCB Tolerance stack and cable misrouting in the assembled product

State matters: A normally closed terminal can remain energized while the normally open net appears inactive. Build the barrier map from the highest credible voltage across each pair during every normal state, required abnormal state, startup/shutdown sequence, and transient condition-not from one schematic snapshot.

 

Why There Is No Universal 3 mm, 6 mm, or 8 mm Rule

Two boards switching 250 VAC can need different distances. One may be plug-connected equipment inside a controlled enclosure; another may be permanently connected industrial equipment. One barrier may be functional, another basic, and another reinforced. One product may be limited to 2,000 m while another is specified for high altitude. The PCB material group, condensation risk, transient environment, waveform and national adoption can also differ.

IEC 60664-1 is a basic insulation-coordination publication for equipment within its scope, but an end-product standard can modify the method, tables, tests, permitted constructions and terminology. Examples include IEC 62368-1 for AV/ICT equipment, IEC 61010-1 for measurement/control/laboratory equipment, IEC 60335-1 plus the applicable part 2 for household appliances, and IEC 61800-5-1 for adjustable-speed drives. Identify the product standard and certification path before freezing the relay footprint.

Question Incorrect shortcut Correct evidence
What spacing is needed for 250 VAC? Copy one value from an online voltage table End-product standard, barrier function, complete voltage model, OVC, PD, material group and altitude
Does an 8 mm relay require an 8 mm PCB gap? Copy the relay package number into global DRC Independent product-level requirement plus exact relay barrier data and board-path measurement
Can a passed hi-pot test approve the layout? Treat a short test as a waiver for geometry and pollution Distance review, materials, conditioning, impulse/dielectric tests and production controls required by the standard

 

Determine Clearance from the Air-Insulation Stress

Clearance is controlled by the voltage stress the air path must withstand. Depending on the governing procedure, that can include required impulse withstand, recurring peak, temporary overvoltage, supply-system voltage, overvoltage category, frequency, field geometry and altitude. A normal RMS label does not describe every stress created by contact arcs, motors, solenoids, transformers, long cables, regeneration, MOVs, or load disconnection.

Clearance input Question to answer Evidence to retain
Insulation function Functional, basic, supplementary, reinforced, or product-specific safeguard? Safety architecture and governing clause
System and working voltage What is the voltage across this exact barrier in every required state? Circuit diagram, tolerance analysis and waveforms
Transient and temporary overvoltage What impulse and abnormal conditions must the barrier survive? OVC/installation basis, SPD coordination and standard method
Frequency and waveform Are high-frequency or non-sinusoidal stresses present? Frequency, duty, dv/dt, recurring peak and measurement method
Altitude What is the product's maximum rated operating altitude? Product specification and permitted correction procedure
Electric-field geometry Is the field homogeneous or strongly non-homogeneous? Mechanical cross-section and electrode geometry

Altitude must be part of the original requirement

The current IEC 60664-1 consolidated record applies directly up to 2,000 m and provides guidance above that altitude. Lower air pressure makes flashover easier, so clearance normally requires the standard's correction method for higher rated altitude. Creepage is not simply multiplied by the same factor, although the accepted surface path still must not undercut a larger clearance requirement for the same barrier.

 

Determine Creepage from Surface Stress and Material

Creepage addresses the long-term path along an insulating surface. Moisture and contamination can conduct leakage current; repeated heating and chemical change can form a carbonized track. The governing inputs usually include the applicable working-voltage measure, insulation function, pollution degree, material group/CTI, surface construction, and valid ribs, grooves or slots.

Creepage input Why it changes the result Relay-PCB action
Working voltage Sustained worst-case stress drives surface tracking risk Use the voltage across the actual barrier, not relay contact rating alone
Pollution degree Dust, moisture, condensation and residue change surface conductivity Justify the PCB microenvironment over life, including storage and startup
Material group / CTI Tracking resistance affects the required surface path in some procedures Specify the exact qualified laminate system; "FR-4" is not a CTI value
Insulation function A protective barrier can require more than a functional separation Name the safeguard and hazard controlled
Surface condition Flux, coating defects, scratches, dust and aging change the real surface Control assembly, cleaning, handling, coating and rework
Geometry Valid slots, grooves, ribs and component walls change the shortest path Use the exact standard's path-counting and minimum-geometry rules

CTI is an input-not a safe distance

Comparative tracking index is measured by a standardized material test and helps classify insulating materials. IEC 60112:2025 explicitly states that its test results are not directly suitable for evaluating safe creepage distance. The result must be used within the applicable insulation-coordination method together with voltage stress, pollution degree, distance and construction.

Do not specify only "FR-4." That name covers many laminate systems with different CTI, material recognition, thickness, resin, temperature capability, copper configuration and coating compatibility. Put the minimum required CTI or material group, exact recognized laminate system, thickness, copper weight, approved alternatives and change-notification requirement on the fabrication drawing and AVL.

Pollution degree describes the local surface

Pollution degree Simplified orientation Design warning
PD1 No pollution or only dry, non-conductive pollution in a proven protected microenvironment An office location or enclosure label alone does not prove PD1
PD2 Normally non-conductive pollution; temporary conductivity may occur through condensation Storage, cold start and thermal cycling can still create condensation
PD3 Conductive pollution or dry pollution expected to become conductive Dust plus humidity can create a persistent leakage path
PD4 Persistent conductivity from conductive dust, rain or other wet conditions An exposed ordinary PCB may not be an acceptable architecture

These descriptions are only orientation. Use the governing definition. An IP enclosure may reduce ingress while still allowing condensation, internal dust, flux residue, insects, conductive wear debris, or chemicals generated by the equipment.

 

Use a Ten-Step Rule for Relay PCB Spacing

  1. Identify the equipment and markets. Select the end-product standard, edition, amendments, national deviations and certification route.
  2. Draw the barrier diagram. Label hazardous, SELV/PELV, grounded, accessible, signal, line, neutral, phase and switched nodes in every relay state.
  3. Assign each insulation function. Record functional, basic, supplementary, reinforced, double or other product-specific safeguard and the hazard it controls.
  4. Determine the working voltage. Analyze the relevant RMS, DC mean, recurring peak, tolerances, converter states and normal worst-case operation.
  5. Determine impulse and temporary-overvoltage conditions. Include OVC, installation position, surge protection, waveform and frequency as the standard requires.
  6. Classify the microenvironment. Justify pollution degree from the actual enclosure, condensation, dust, process residue and service life.
  7. Specify insulating materials. Obtain qualified CTI/material-group evidence for the PCB and relevant component surfaces; treat unknown data conservatively.
  8. Apply altitude and special procedures. Use maximum rated altitude and check high-frequency, non-sinusoidal, coated-board and field-geometry rules.
  9. Read the correct requirements. Keep creepage and clearance separate, apply the exact table/procedure, and record the clause, assumptions, interpolation and correction factors.
  10. Implement and verify. Select the relay, create CAD rules and keepouts, audit Gerbers/CAM, inspect assembled samples, measure the shortest paths and complete required tests.

Documentation rule: For every safety-related spacing value, retain the barrier name, separated circuits, standard and edition, clause/table, insulation function, voltage inputs, OVC, pollution degree, material group, altitude, calculated minimum, CAD target, measured assembled minimum and approval status.

 

Read Relay Datasheet Insulation Data Correctly

A high-insulation relay can make a safe layout practical, but its datasheet does not certify unrelated PCB paths. Compare the exact part number and suffix. Different variants in one family can change pin geometry, insulation construction, material group, contact form, approval and external spacing.

Datasheet field What it supports What it does not prove
Coil-to-contact clearance Named air path inside/on that exact relay PCB copper, solder, connector, chassis or end-product compliance
Coil-to-contact creepage Named surface path in the relay insulation system The PCB laminate path or all external component surfaces
Dielectric strength Withstand under the stated voltage, waveform, duration and barrier A universal continuous working-voltage or creepage approval
Impulse withstand Performance in the stated impulse test Every surge environment, altitude or repetitive waveform
Reinforced-insulation statement Component evaluation under named conditions and standards Automatic reinforced insulation in every end product
Recommended footprint Hole, pad and orientation guidance Permission to place unrelated copper, test points or vias under the relay

Official product data illustrates why model specificity matters. One current Omron G2RL family page states 8 mm minimum clearance and creepage for that family, while other relay constructions publish different values. Those numbers are component facts-not universal PCB requirements. For a QIANJI candidate, request the exact coil-contact and contact-contact distances, dielectric/impulse data, material and approval conditions for the full order code.

Review QIANJI's PCB relay range as a starting point, then approve only the exact model whose insulation geometry, load rating, coil, footprint, manufacturing evidence and certification scope fit the project.

 

Measure the Finished Conductive Edges, Not CAD Centers

The manufactured assembly determines the shortest path. Measure from the nearest conductive surfaces, including finished copper, annular rings, plated barrels, solder, component leads, screw heads, shields, heat sinks, connectors and conductive contamination. A center-to-center pad measurement can overstate the real distance.

Feature Measurement focus Verification
Tracks, pours and pads Nearest finished copper or solder edge Layer-by-layer CAD query, Gerber/CAM review and first article
Plated holes and vias Barrel, annular ring, solder and exposed probe hardware Inspect both board sides and fabrication data
Relay pins and solder fillets Exposed pin, lead protrusion and worst permitted solder spread Actual component, assembly cross-section and process-capability samples
Board edge and hardware Copper/pin to chassis, rail, screw, adjacent PCB or cable lug Mechanical tolerance stack in final mounting orientation
Slot or groove Valid surface path around the cutout plus separate air path across it Finished slot dimensions, edge quality and governing geometry rule
Component body or barrier Only accepted insulating material and construction Material declaration, drawing and standard-specific assessment

Through-hole relay paths can run across the top surface, bottom surface, relay housing, or a combination. Clearance can pass diagonally between protruding pins or solder cones. Inner-layer copper is not ordinary external creepage: if it enters the isolation corridor, the construction must be evaluated as solid insulation through the board under the applicable rules.

 

Use Slots, Keepouts and Orientation Deliberately

An all-layer isolation corridor is often the clearest default. Keep hazardous and control domains visible, place coil pins toward the low-voltage side, place contact/load routing near the appropriate connector, and exclude copper, vias, test pads, fiducials and mechanical objects from the barrier.

Layout strategy Benefit Boundary or trade-off
All-layer isolation corridor Creates a visible no-copper/no-via barrier Consumes board area and can constrain high-current routing
Relay and connector orientation Reduces crossings and keeps voltage domains separate Must still satisfy vibration, thermal, current-path and enclosure needs
Controlled unplated slot Can extend a valid surface path without greatly enlarging the PCB May not improve clearance; adds routing tolerance and mechanical weakness
Qualified rib or barrier Can lengthen a path when accepted by the standard Material, height, width, tolerance and assembly control determine whether it counts
Higher-CTI laminate May reduce creepage in the applicable procedure Does not reduce impulse-controlled clearance; material must be locked
Larger high-insulation relay Reduces reliance on special PCB processing May increase footprint, price, coil power or sourcing constraints

Create separate CAD constraints for external copper, internal copper, pads, vias, polygons, board edge and mechanical objects. Give rules meaningful names such as HV_TO_SELV_REINF_PD2_4000M. After every ECO, review automatic copper-pour regeneration, teardrops, thermal reliefs, via stitching, test fixtures and panel tooling.

Do not solve spacing by making a high-current trace too narrow or long. Insulation and temperature rise must pass together. Use appropriate copper thickness, pad area, approved layer sharing or bus structures, short current paths and thermal validation without placing conductive heat spreaders inside the barrier.

 

Do Not Count Ordinary Solder Mask Automatically

Design the spacing as uncoated unless the applicable product standard and certification evidence accept the exact mask or coating construction. UL Solutions explains that, for IEC 62368-1, an ordinary solder mask generally is not a suitable coating unless it passes the specified coated-board test. Even then, the permission can be limited to conductor patterns and differs from a conformal coating that covers leads and other assembly features.

Close-up of green solder mask covering conductors on a printed circuit board

Solder mask supports PCB manufacturing, but its visible presence is not automatic evidence that a safety spacing may be reduced. Image: Humanoc, Wikimedia Commons, CC BY-SA 4.0.

Silkscreen, adhesive and an unknown plastic part also should not be counted as insulation simply because they sit in the gap. Analog Devices' isolation-layout guidance warns that silkscreen and solder mask are not reliable insulators for the discussed isolation barrier and that a ground plane pulled underneath reduces the PCB barrier.

 

Treat Conformal Coating and Potting as Qualified Systems

IEC 60664-3 covers assemblies protected against pollution by coating, potting or moulding. It describes Type 1 protection as improving the microenvironment and Type 2 protection as similar to solid insulation. A bottle labeled "high dielectric strength" is not enough. The permitted reduction and tests come from the governing method.

Construction Possible role Control needed
Ordinary solder mask Manufacturing protection; normally no automatic insulation credit Exact product-standard permission and tested construction
Type 1 coating Improves the protected microenvironment Material, coverage, thickness, cure, defects, aging and required tests
Type 2 protection Evaluated similarly to solid insulation Geometry, scratch/visual/electrical/environmental testing and process traceability
Potting or moulding Can replace an air path with a solid-insulation construction Voids, partial discharge, adhesion, thermal expansion, moisture, aging and component stress
Conformal coating being applied across a printed circuit board assembly

Coating is a manufacturing process, not merely a material selection. Coverage, masking, cure, bubbles, pinholes, edge thickness, inspection and repair all affect the qualified result. Image: Encik Tekateki, Wikimedia Commons, CC BY-SA 4.0.

Control supplier, material, viscosity, thickness window, coverage, masking, cure, cleanliness, adhesion, bubbles, pinholes, sharp edges, component compatibility, repair and inspection. Relay vents, contacts, connectors, test points, heat sources and unsealed components may need special treatment. A substitute coating or process change can invalidate the evidence used to reduce spacing.

 

Worked Example: Use Numbers Only After the Standard Decision

Illustrative workflow only: The values below are assumed inputs supplied by a compliance engineer for one defined construction. They are not a spacing table and must not be transferred to another product.

Assume a 24 V control circuit drives a relay switching a hazardous supply, and the architecture requires a reinforced barrier between the control and load domains. After applying the correct end-product procedure, the compliance record identifies a 4.0 mm base clearance at the reference altitude and a 6.4 mm creepage requirement for the selected working voltage, pollution degree and PCB material group.

If the product is rated to 4,000 m and the applicable method assigns a 1.29 clearance correction factor for this case, the corrected clearance is 4.0 × 1.29 = 5.16 mm. The assumed creepage remains 6.4 mm, and the planar design must satisfy the larger requirement before manufacturing margin. The PCB team then sets a larger CAD target to cover copper etch, drill/slot position, pad size, relay-pin position, solder spread, assembly alignment, measurement uncertainty and supplier variation.

Step Illustrative result Release evidence
Barrier objective Reinforced control-to-load barrier Safety architecture and product-standard clause
Base clearance Assumed 4.0 mm at reference altitude Correct procedure, voltage/impulse/OVC/waveform assumptions
Altitude-corrected clearance 5.16 mm in this assumed case Factor from applicable edition and equipment method
Creepage Assumed 6.4 mm Working voltage, insulation function, PD and material evidence
CAD target Greater than the controlling theoretical value Documented tolerance and company margin
Manufactured minimum Measured on worst-case assembled samples First-article report and production control plan

The lesson is the workflow, not 6.4 mm. An 8 mm relay can offer useful margin but does not dictate the board requirement. A nominal board gap also fails if a solder cone, inner via, screw or unqualified coating creates another path.

 

Control Manufacturing as Part of the Insulation System

Control point Specify or inspect Failure prevented
Laminate Exact material system, CTI/group, recognition, thickness, copper and PCN Unapproved material changes tracking or solid-insulation performance
Copper and registration Minimum finished edge spacing after etch and alignment tolerance Nominal CAD gap becomes smaller in production
Drills and slots Finished width/location, edge quality, plating prohibition and routing tolerance Slot fails to provide the credited path
Solder and leads Maximum fillet, lead protrusion, solder balls and first-article inspection Assembly creates a shorter conductive edge
Flux and cleaning Chemistry, ionic cleanliness, drying, storage, handling and relay compatibility Residue and moisture accelerate leakage or tracking
Substitutions and hardware Exact relay suffix, screw/washer/standoff/shield and harness tolerance Form-fit change or metalwork enters the barrier

Cleanliness is a reliability variable. Flux residue, fibers, dust, metal particles, condensation and coating contamination can turn a nominal insulator into a leakage path. Validate storage between processes, washing/drying, manual rework, gloves, coating preparation and final packaging. The relay itself may have restrictions on flux, cleaning chemistry or coating around vents and seals.

 

Common Review Failures and Corrections

Mistake Why it fails Correction
Using a generic "250 V" web table Assumptions may not match standard, OVC, PD, CTI, insulation function or altitude Recalculate from the end-product standard and document inputs
Copying relay 8 mm into PCB DRC Component data covers named relay paths, not every board path Create barrier-specific rules from the product requirement
Measuring pad center to center Finished conductive edges and solder are closer Measure edge to edge with fabrication and assembly tolerances
Counting solder mask automatically Ordinary mask may have no qualified insulation credit Design uncoated or qualify the exact system
Adding a decorative narrow slot It may not count and may not improve the air path Specify valid finished geometry and verify both paths
Routing an inner plane through the corridor External spacing is replaced by a solid-insulation construction Use all-layer keepout or qualify the stackup and solid insulation
Bare board passes; assembly fails Solder, leads, hardware, connector or harness shortens the path Inspect and measure worst-case production assemblies

 

Relay and PCB Supplier RFQ Checklist

  • Application basis: end-product standard, edition, markets, certification body and insulation objective.
  • Voltage model: system and working voltage, RMS/DC, recurring peak, impulse, temporary overvoltage, frequency and load transients.
  • Environment: pollution degree, maximum altitude, temperature, humidity, condensation, dust, chemicals and enclosure.
  • Relay: exact suffix; coil-contact, contact-contact and open-contact data; dielectric/impulse tests; material group; footprint; approvals and conditions.
  • PCB: exact laminate, CTI/material group, recognition, thickness, copper, stackup, mask and approved alternates.
  • Slots: minimum finished width/length, location tolerance, plating control, edge quality and fabrication capability.
  • Coating or potting: material, qualification, protection type, thickness, coverage, cure, masking, inspection, repair and traceability.
  • Assembly evidence: first-article dimensions, solder spread, lead protrusion, cleanliness, coating coverage and required test results.
  • Change control: PCN requirements for relay, factory, plastics, terminals, laminate, coating, stackup, PCB supplier and process.

For a useful QIANJI review: send the exact product standard, barrier diagram, relay coil and contact voltages, load, insulation objective, OVC, pollution degree, altitude, PCB material/CTI, required distances, footprint constraints and target approvals. QIANJI can then screen exact relay models and samples against the defined component requirements.

 

Frequently Asked Questions

What is the minimum creepage distance for a 250 VAC relay PCB?

There is no universal value. Use the end-product standard, voltage across the exact barrier, insulation function, pollution degree, PCB material group and construction. A larger clearance requirement can also control the accepted planar path.

What is the minimum clearance for 250 VAC?

It cannot be determined from 250 VAC alone. Clearance can depend on system voltage, OVC, required impulse or temporary-overvoltage withstand, recurring peak, frequency, field geometry, insulation function and altitude.

If a relay has 8 mm creepage and clearance, must the PCB use 8 mm?

Not automatically. The product requirement may be lower, equal or higher, and the published 8 mm may apply only to one named relay barrier. The board and complete assembly must independently preserve every required path.

Does a PCB slot increase both creepage and clearance?

A valid slot often increases the surface path and therefore creepage. It may not increase the shortest air path because an arc can cross the opening directly or diagonally. Its finished geometry must meet the governing measurement rules.

Can conformal coating reduce spacing?

A qualified coating system can improve the microenvironment or be evaluated as another insulation construction under the permitted method. It does not automatically eliminate the air path. Material, application, defects, conditioning, inspection and testing must all be controlled.

Can a ground plane run beneath the relay isolation barrier?

Only if the complete solid-insulation construction is intentionally evaluated. A plane can shorten the barrier and change the insulation type. An all-layer keepout is the clearer default for a safety-critical isolation corridor.

How should spacing be checked in production?

Verify Gerber/CAM data, laminate, finished slots, copper-edge spacing, relay identity, solder spread, lead protrusion, hardware, cleanliness and coating coverage. Measure representative worst-case assemblies and complete the dielectric, impulse, environmental and routine tests in the compliance plan.

 

Final Design Review Checklist

  • The correct end-product standard, edition, amendments and national adoption are recorded.
  • Every insulation barrier and relay contact state is shown on an annotated diagram.
  • Working, recurring peak, impulse, temporary-overvoltage, abnormal and frequency stresses are documented.
  • Insulation function, OVC, pollution degree, altitude and material group are justified.
  • The exact relay suffix supports the required internal insulation, open-contact behavior and approvals.
  • CAD rules cover all copper layers, pads, vias, polygons, board edge, slots, test points and mechanical objects.
  • Paths are measured from the nearest finished conductive edges on the assembled product.
  • Solder, cleaning, coating/potting, hardware and substitutions are controlled by drawings and work instructions.
  • Required dielectric, impulse, environmental, abnormal and production tests are complete.
  • Changes to relay, PCB material, layout, supplier, coating, slot or enclosure trigger re-evaluation.

Need a PCB relay reviewed against your insulation plan?

Send QIANJI your circuit voltages, load, exact barrier objective, product standard, pollution degree, altitude, PCB material, required footprint and approval targets for model-level screening and sample discussion.

Send Your Design Requirements

 

Technical References

Safety note: Standards, amendments, national adoptions, relay specifications and certification conditions can change. Confirm the current end-product standard, exact relay part number and certificate, real voltage waveforms, insulation objective, pollution degree, material group, altitude, PCB stackup, manufacturing tolerances and required tests with qualified compliance personnel or the certification body before design release. Mains-connected, medical, automotive, railway, hazardous-location and other high-consequence equipment require application-specific assessment.